Sketch Flange
Pipe flange with two mounting lugs, drawn as one constraint sketch: - the right lug is drawn once (two lines tangent to the flange circle and to the lug's end arc) and mirrored with <mirrorEntities>, so both lugs stay identical as params change; - the bolt circle is one hole and a <circularPattern>, its copies tied by rotation constraints rather than computed coordinates.
examples/sketch-flange.tsx on GitHub
bunx tscad dev examples/sketch-flange.tsx/**
* Pipe flange with two mounting lugs, drawn as one constraint sketch:
* - the right lug is drawn once (two lines tangent to the flange circle and to the lug's end
* arc) and mirrored with <mirrorEntities>, so both lugs stay identical as params change;
* - the bolt circle is one hole and a <circularPattern>, its copies tied by rotation
* constraints rather than computed coordinates.
*
* tscad dev examples/sketch-flange.tsx
*/
import { defineParams, edges, type ParamValues } from "tscad"
export const params = defineParams({
diameter: { type: "number", default: 80, min: 40, max: 200, step: 1, unit: "mm", label: "Flange Ø" },
bore: { type: "number", default: 32, min: 10, max: 120, step: 1, unit: "mm", label: "Bore Ø" },
bolts: { type: "int", default: 6, min: 3, max: 16, label: "Bolts" },
boltCircle: { type: "number", default: 58, min: 25, max: 180, step: 1, unit: "mm", label: "Bolt circle Ø" },
boltHole: { type: "number", default: 6.6, min: 2, max: 20, step: 0.1, unit: "mm", label: "Bolt hole Ø" },
lugReach: { type: "number", default: 62, min: 30, max: 150, step: 1, unit: "mm", label: "Lug hole offset" },
lugRadius: { type: "number", default: 10, min: 5, max: 30, step: 0.5, unit: "mm", label: "Lug end radius" },
lugHole: { type: "number", default: 8.5, min: 3, max: 20, step: 0.1, unit: "mm", label: "Lug hole Ø" },
thickness: { type: "number", default: 8, min: 3, max: 25, step: 0.5, unit: "mm", label: "Thickness" },
})
export default function Flange(p: ParamValues<typeof params>) {
const R = p.diameter / 2
// derived so any slider combination stays a valid flange, with at least `gap` of material
// between features (the top-edge fillet needs room)
const gap = 4
const bore = Math.min(p.bore, p.diameter - 4 * gap)
const lugR = Math.min(p.lugRadius, 0.45 * R)
const reach = Math.max(p.lugReach, R + 0.3 * lugR) // the lug must stick out of the disc
const lugHole = Math.max(1, Math.min(p.lugHole, 2 * (lugR - gap)))
// bolt circle between the bore and the rim; fewer bolts if they would touch
const hole = Math.min(p.boltHole, R - bore / 2 - 2 * gap)
const bc = Math.min(Math.max(p.boltCircle / 2, bore / 2 + hole / 2 + gap), R - hole / 2 - gap)
const maxBolts = hole > 1 ? Math.floor(Math.PI / Math.asin(Math.min(1, (hole + gap) / (2 * bc)))) : 0
const bolts = Math.min(p.bolts, maxBolts)
const withBolts = hole > 1 && bolts >= 2
return (
<part name="flange" material="steel">
<fillet radius={1} edges={edges.max("z")}>
<extrude height={p.thickness}>
<sketch>
<point id="o" fixed />
<line id="axis" from="o" to="up" vertical length={R} construction />
{/* right lug: centre on the X axis, end arc, two tangent lines into the flange */}
<point id="lug" />
<horizontal a="o" b="lug" />
<dimension a="o" b="lug" dx={reach} />
<arc id="lugEnd" center="lug" from="l1" to="l2" radius={lugR} />
{/* rough positions: where the lug's lines meet the lug and the disc */}
<point id="l1" x={reach} y={-lugR} />
<point id="l2" x={reach} y={lugR} />
<point id="m1" x={0.7 * R} y={-0.7 * R} />
<point id="m2" x={0.7 * R} y={0.7 * R} />
<line id="lugTop" from="l2" to="m2" />
<line id="lugBottom" from="m1" to="l1" />
{/* the flange circle between the lugs: top and bottom arcs */}
<arc id="top" center="o" from="m2" to="m2'" radius={R} />
<arc id="bottom" center="o" from="m1'" to="m1" equal="top" />
{/* the lug's lines are outer tangents: the disc's and the lug's centres both on their
left (`side` picks that branch whatever the sizes) */}
<tangent a="lugTop" b="lugEnd" side="left" />
<tangent a="lugBottom" b="lugEnd" side="left" />
<tangent a="lugTop" b="top" side="left" />
<tangent a="lugBottom" b="bottom" side="left" />
<mirrorEntities about="axis" of={["lugEnd", "lugTop", "lugBottom"]} />
{/* holes: bore, lug holes, bolt circle */}
<circle center="o" diameter={bore} />
<circle center="lug" diameter={lugHole} />
<circle center="lug'" diameter={lugHole} />
{withBolts && (
<>
<circle id="bolt" center="b" diameter={hole} />
<dimension a="o" b="b" distance={bc} />
<line from="o" to="b" angle={90 + 180 / bolts} construction />
<circularPattern center="o" count={bolts} of={["bolt"]} />
</>
)}
</sketch>
</extrude>
</fillet>
</part>
)
}